Animation displayed in Ceiling Hook -- SolidWorks 2014 (with caption and audio narration)

Serial No. 214

Animation displayed in Ceiling Hook -- SolidWorks 2014 (with caption and audio narration)

In this video, we will demonstrate how to apply the different type of mates in the assembly environment for creating the animation.
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To watch full sketching video of this model 'Ceiling Hook', please visit on my another associated video named as 'Ceiling Hook with Animation' (SolidWorks).

Click the following link to get the model file: - http://bit.ly/31K8Bvu 
 

 

 

Transcription of the Video

1. Create a new assembly file.
2. The ‘Begin Assembly’ command is already activated in the assembly design window.
3. Click Browse button, place the part file ‘Hook’.
4. First of all, open the visibility of ‘View Origin’ of the assembly.
5. Click the View Origin point button to place the file, centre of the assembly.
6. Choose ‘Isometric View’.
7. In the same way, place one more part file-name ‘Circular Ring.’
8. Rotate the part by using ‘Move with Triad’ tool.
9. Save the assembly with the name ‘Ceiling Hook’ and edit the ‘Hook’ part file.
10. Create a new sketch over the ‘Front Plane’ and take a project of this circular edge by using ‘Convert Entities’ command.
11. Finish the sketch and return back to the assembly environment.
12. Select the Front Plane of assembly and Right Plane of Circular Ring and mate it.
13. It will apply a Coincident mate.
14. Move the Circular Ring slightly.
15. Activate the ‘Mate’command, select tangent face of Circular Ring and arc along the path of hook, and apply the tangent mate.
16. Select the Front Plane of Circular Ring, Right Plane of assembly and apply the Coincident mate.
17. Edit the Circular Ring part and activate the Axis tool.
18. Choose ‘Point and Face/Plane’ option as this particular type of selection.
19. Many options available here, choose any option as you need.
20. Select the origin point and Front Plane of assembly to create the axis.
21. Click OK to execute the command.
22. Open the visibility of axis by using ‘View Axes’ command.
23. Return to the assembly view.
24. Activate the ‘Mate’ command, select the assembly origin and Axis of Circular Ring and apply it.
25. Select the Coincident2 mate and suppress the mate.
26. Let see here, the Circular ring part rotates about the inner periphery of Hook with the help of tangent and axis mate.
27. Create an Axis between origin point of assembly and end point of arc in assembly.
28. Create a new work plane between front plane and this axis.
29. A work plane has been created along the axis.
30. Apply an angle mate between Front plane of Circular Ring and Plane1.
31. Set the angle value to 0 degree.
32. Go on the Evaluate tab and activate the ‘Measure’ command.
33. Select the Top Plane and Plane1 and monitor the value.
34. Copy the angle value and calculate the value as shown (290.39126 degree).
35. In the next section, we will create animation on the Circular Ring its start value is 0⁰ and end value 290.39126⁰.
36. Choose Front View, in the Orientation dialog box, activate the ‘New view’ command and set its name as ‘View2'.
37. In the same manner, choose Isometric View, set its name as ‘View1’.
38. These saved views will be used later in animation timeline.
39. Select the Motion Study tab, click the Orientation and Camera button in the animation timeline.
40. Right click on the time bar and select Move Time Bar option, set the time on 2 second.
41. Copy the View-1 key and place the key on 2 seconds.
42. Pause 2 seconds on the View-1 position.
43. Move the time bar on 7 seconds and add the new key.
44. Minimize the animation timeline and choose View-2, in the Orientation dialog box.
45. Return back to the animation timeline and right click over the 7 seconds key and select ‘Replace Key’ option.
46. Time taken 5 seconds in changing from view-1 to view-2 position.
47. In the Mates folder, select the Angle1 mate and add the key in the timeline by using Add key button.
48. Right click the animation timeline, move the time bar at 22 seconds.
49. Right click on the Angle1 and select Edit Dimension option, paste the specified angle, click OK.
50. Click the ‘Collapse Motion Manager’ button.
51. Click play animation button to check the motion.
52. Now we will create some modifications in the animation.
53. Right click the start key point time of angle mate and move the key position at 9 seconds in the Edit time dialogue box.
54. Right click the end key point time of angle mate and move the key position at 24 seconds.
55. Stop the animation 2 seconds between View-2 and starting key point of Angle1 mate.
56. Go on the Orientation and Camera tab, copy the View-2 key and paste the key over 24 seconds in the timeline.
57. Move the time bar at 26 seconds, right click and paste View-2 key.
58. Pause the animation for 2 seconds at View-1 position.
59. Copy the end key point of Angle1 mate and paste key on 26 seconds.
60. Stay in the still position for 2 seconds.
61. Repeat the whole animation in reverse order to come back in starting position.
62. Minimize the animation timeline and clear the screen.
63. Click ‘Play from Start’ button and start the animation.
64. Return back to the assembly environment and save the file.

Ceiling Hook with Animation (SolidWorks 2014 Tutorial)

Serial No. 93

Ceiling Hook with Animation (SolidWorks 2014 Tutorial)

Click the following link to get the model file: -http://bit.ly/31K8Bvu

Ceiling Hook-Autodesk Inventor 2013 (with caption and audio narration)

 

Serial No. 16

Ceiling Hook-Autodesk Inventor 2013 (with caption and audio narration) 

 

Click the following link to get the model file: - http://bit.ly/2mcyc0m

 

Transcription of Video

Ceiling Hook: -- Modelling and apply motion in it through Drive Constraint

1. Create a New ‘Standard (in).ipt’ Part file.
2. Create a new sketch on XY Plane of Part.
3. Draw a Circle of 0.43800 inch diameter, coincident with Auto projected part origin.
4. Draw a Line of length 0.25 inch parallel to Y axis.
5. The midpoint of this line should lie on the X axis.
6. Apply a Coincident Constraint between the end point of the line and the periphery of the circle.
7. Create a new Line by taking the offset of this chord.
8. Give the dimension of 0.15625 inch on this line.
9. This line should be 1.5 inch away from the chord and its midpoint should lie on X axis.
10. Start Line tool and join both the ends of this line with the end points of chord of circle.
11. Convert all the sketches into construction geometry.
12. Start the Centre Point Arc tool.
13. Select the Auto projected part origin first then the end points of chord of the circle.
14. Finish the sketch by clicking the Finish Sketch Icon.
15. Create a new sketch on XZ plane.
16. Take the project of last drawn arc and convert it to construction geometry.
17. Create a circle of .094 inch diameter on the end point of this projected line.
18. Finish the sketch.
19. Activate Sweep Tool from the Create Panel of Model Tab.
20. It will automatically select the small circle created on the Sketch2 as Profile and arc drawn on Sketch1 as path.
21. Click OK.
22. Change the Model colour to Flaked Reflective-Beige.
23. Save the Part file with the name ‘Hook’.
24. Open the visibility of Sketch1 in Browser Bar.
25. Create a new Work Plane on this point parallel to YZ Plane of the Part.
26. Draw a sketch on this work plan.
27. Take the project of end point of the vertical line.
28. Draw a Circle of 0.0625 inch diameter.
29. Finish the sketch.
30. Start Loft Tool, select small circle and circular edge of the part.
31. Click OK.
32. Close the visibility of Sketch1 and Work Plane1.
33. Start Mirror tool from the Pattern panel of Model Tab.
34. Select Loft1 from the Browser Bar as feature.
35. Select XZ Plane from the Browser Bar as Mirror Plane.
36. Click OK.
37. Save the file and close it.
38. Create a New ‘Standard (in).ipt’ Part file.
39. Create a new sketch on XY Plane of Part.
40. Draw a Circle of 1 inch diameter, coincident with Auto projected part origin.
41. Finish the sketch by clicking the Finish Sketch Icon.
42. Create a new sketch on XZ plane.
43. Take the Project of big circle and convert it to construction geometry.
44. Create a circle of 0.094 inch diameter on the end point of this projected line.
45. Finish the sketch.
46. Start Sweep Tool, select small circle as profile and select big circle as path.
47. Click OK.
48. Change the Model colour to Flaked Reflective-Beige.
49. Save the file with the name ‘Circular Ring’ and close it.
50. Create a New ‘Standard (in).iam’ Assembly and Save it with the name ‘Ceiling Hook’.
51. Select Place Component from the marking menu and place the ‘Hook’ in the Assembly.
52. Place ‘Circular Ring’ in the Assembly.
53. Align the Circular Ring according to Hook by using Rotate Component Tool.
54. Apply a Tangent Mate between Circular Ring and Hook.
55. Apply a Mate Constraint between XY Plane of Assembly and YZ Plane of Circular Ring.
56. Edit the Circular Ring in the Assembly by double clicking it.
57. Activate Work Axis Command.
58. First select the Centre Point of Hook, then the Z Axis of Hook from the Browser Bar.
59. In this way a new Work Axis which is Adaptive to Z Axis of Hook is created.
60. Return to Assembly by clicking Return Icon.
61. Suppress the Tangent Mate from the Browser Bar, which was applied earlier.
62. Now the Circular Ring is ready to move along the Hook.
63. Create an Axis in the Assembly on the basis of two points on the periphery of Hook as displayed.
64. Go to Work Features panel and click the drop down of Work Plane command.
65. Select ‘Angle to Plane around Edge’ command.
66. First select XY Plane of Assembly, then select Work Axis1 of Assembly.
67. Click OK.
68. Activate an Angle Constraint, first select Work Plane1 of the Assembly, then select XY Plane of Circular Ring and at last select XY Plane of Assembly.
69. Click OK.
70. Open the visibility of XZ Plane of Assembly.
71. Measure the Angle between XZ Plane of Assembly and Work Plane1 of Assembly.
72. The magnitude of this angle is 145.2 degree.
73. Click the Selection drop drown menu and choose ‘Select Sketch Features’ command in the Quick Access Toolbar.
74. Close the visibility of unnecessary work planes and work axis.
75. Set the browser from Assembly View to Modeling View by using the Toggle at the top of the Browser Bar.
76. Select the Angle:2 constraint under the Constraints folder in the Browser Bar and Change its name as ‘Drive’ by clicking twice slowly.
77. Right click the ‘Drive’ Constraint and select ‘Drive Constraint’ Tool from the context menu.
78. In the Drive Constraint dialog box, set the End value to (145.2*2) degree.
79. Click the more button to expand the dialog box, enter the value 0.5 degree in the ‘Increment’ field.
80. Clear the screen by activating the Clean Screen command.
81. Click the Forward Button to display motion in ‘Ceiling Hook’.
82. Click Reverse Button to return at previous position.